|
[Sponsors] |
August 12, 2011, 05:42 |
Converge problem
|
#1 |
Senior Member
siamak rahimi ardkapan
Join Date: Jul 2010
Location: Copenhagen, Denmark
Posts: 220
Rep Power: 18 |
Hi All,
I want to simulate air movements in a room. I have a converge problem. Also I got this error "BiCGStab did not converge !" in the residual page, Tdr in k-epsilon diverge. Do you know how to solve the problem? the surface mesh quality is higher than 0.5 and volume mesh quality is higher than 0.1. Thanks in advance for your help |
|
August 12, 2011, 05:53 |
|
#2 |
Senior Member
Join Date: Dec 2010
Posts: 135
Rep Power: 16 |
1. Idea: maybe use 1st order and increase in later steps to 2nd order
2. 2. Idea. Use k-omega SST Model |
|
August 12, 2011, 07:43 |
Thanks for the reply
|
#3 |
Senior Member
siamak rahimi ardkapan
Join Date: Jul 2010
Location: Copenhagen, Denmark
Posts: 220
Rep Power: 18 |
I did the ideas. But they did not change the result. I tried other turbulent models but the results were not better than the first one.
Thanks again for your reply |
|
August 12, 2011, 08:35 |
|
#4 |
Senior Member
Join Date: Dec 2010
Posts: 135
Rep Power: 16 |
I assume u r running a steady simulation......just give the implicit unsteady a try....
I know this is very general, but maybe it works.... |
|
August 19, 2011, 08:16 |
Thanks for the reply
|
#5 |
Senior Member
siamak rahimi ardkapan
Join Date: Jul 2010
Location: Copenhagen, Denmark
Posts: 220
Rep Power: 18 |
I tried as you said.
I changed the initial conditions and it improved the convergence, but still I can see some fluctuations after 60 iterations. I will try to improve the quality of mesh to see if it can influence. Best Regards |
|
August 19, 2011, 19:50 |
|
#6 |
Senior Member
Vieri Abolaffio
Join Date: Jul 2010
Location: Always on the move.
Posts: 308
Rep Power: 17 |
increasing the mesh quality is generally a good idea.
you might also try to check where the simulation diverges. also try to reduce the underrelaxation factors. |
|
August 29, 2011, 08:17 |
|
#7 |
Senior Member
Join Date: Dec 2010
Posts: 135
Rep Power: 16 |
well, at least check your geometry and your interfaces. There might be somethwing wrong.....
|
|
September 3, 2011, 08:51 |
|
#8 |
Senior Member
Join Date: Oct 2009
Location: Germany
Posts: 636
Rep Power: 22 |
High mesh quality does not mean, the mesh is good for this problem. Is it fine enough?
Is the room closed? I mean, totally enclosed by walls? Do you run compressible or incompressible? |
|
November 15, 2011, 18:32 |
|
#9 |
Senior Member
Join Date: Oct 2009
Location: Germany
Posts: 636
Rep Power: 22 |
Maybe a little bit too late, but it might help other people with the same issue.
It seems, the message just means, the AMG solver for one equation did not reach it's convergence criteria. I would ignore the message as long as the residals don't behave weird and the result is fine. By the way, it's not critical when a residual goes a little bit up as residuals in Star-CCM+ are normalized. |
|
November 15, 2011, 19:45 |
|
#10 |
Senior Member
Joern Beilke
Join Date: Mar 2009
Location: Dresden
Posts: 539
Rep Power: 20 |
"BiCGStab did not converge !" means, that the calculation stops. So it does not really help to ignore the message ;-)
I got this error when I tried to run an airbag gasgenerator simulation with realgas and a mixture of different species. The only way to overcome the problem was using the coupled solver. |
|
November 16, 2011, 18:34 |
|
#11 |
Senior Member
Join Date: Oct 2009
Location: Germany
Posts: 636
Rep Power: 22 |
It does not mean, the calculation stops. It means only the AMG solver could not reach the convergence criteria within the defined number of steps and the residuals didn't go down anymore. But you don't know anything about the difference. For example, the convergence criteria for the AMG solver is 0.1 (which is the default setting), but it reaches only 0.10000001 within the (default) 30 steps - you will get the "BICGStab did not converge" message, although there's nearly no difference in the solution.
|
|
November 16, 2011, 19:05 |
|
#12 |
Senior Member
Joern Beilke
Join Date: Mar 2009
Location: Dresden
Posts: 539
Rep Power: 20 |
At least my testcase stops when I get this error:
"BiCGStab did not converge ! A floating point exception has occurred: floating point exception [Invalid operation]. The specific cause cannot be identified. Please refer to the troubleshooting section of the User's Guide." |
|
November 16, 2011, 19:57 |
|
#13 |
Senior Member
Join Date: Oct 2009
Location: Germany
Posts: 636
Rep Power: 22 |
Yeah, but the reason why it stopped was the floating point exception. That's somehting completely different. A floating point exception always means the simulation stops, and it can also occur without ever using BICGStab.
Also you can get a non-converged BICGStab without getting a floating point exception, that just depends on your physics. And it doesn't harm to read more carefully. I've written "I would ignore the message as long as the residals don't behave weird and the result is fine." |
|
November 17, 2011, 14:47 |
Bi Conjugate Gradient Stabilized not converging
|
#14 |
Member
Paul Hancock
Join Date: Mar 2009
Location: Bellingham, WA
Posts: 31
Rep Power: 17 |
The online documentation indicates that BiCon is a solution acceleration method for the AMG solver. Turn it off.
This message started to appear in some of my cases in v6.04 - I haven't made the switch to v6.06 yet. Siara817, what version of the code are you using? |
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
[Commercial meshers] Handling cyclic BC from gambit to openfoam for a cascade airfoil problem - OF 1.6 | maverick | OpenFOAM Meshing & Mesh Conversion | 2 | June 18, 2011 05:36 |
Velocity profiles problem behind the elbow (3D problem) | kabat73 | FLUENT | 8 | May 9, 2010 05:26 |
converge problem | snowshovel | CFX | 13 | January 18, 2007 22:05 |
Converge problem of 3D free jet flow | Jen | FLUENT | 11 | January 24, 2005 01:21 |
problem with using colocated code | Jack | Main CFD Forum | 0 | December 15, 2002 01:15 |