[nzy102]

Hi Guys:

I am running foam 1.5 with a timeVaryingUniformFixedValue BC. Here is the format I used in my bc:

type timeVaryingUniformFixedValue;
fileName "time-series";
boundAction clamp; // (error|warn|clamp|repeat)

i tried both relative path and complete path for the "time-series" file. And the format of the file is consistent with the old version 1.4.1, and it is something like:

{
t0 p0
t1 p1
t2 p2
....
}

when I ran my stuff, I got an error:

================================================== =
Reading transportProperties

Reading field p

Reading field U



keyword outOfBounds is undefined in dictionary "/home/nzy102/OpenFOAM/nzy102-1.5/run/tutorials/icoFoam/pediatric_aorta_4-e_test mesh_pulsatile_resistancenewbc_zeroGradU/0/U::inlet"

file: /home/nzy102/OpenFOAM/nzy102-1.5/run/tutorials/icoFoam/pediatric_aorta_4-e_testm esh_pulsatile_resistancenewbc_zeroGradU/0/U::inlet from line 61 to line 63.

From function dictionary::lookupEntry(const word& keyword) const
in file db/dictionary/dictionary.C at line 213.

FOAM exiting
================================================== =

Anybody here has a clue what is wrong?

Thank you.

Ning

[olesen]

Try something like this:

fileName "$FOAM_CASE/time-series";
outOfBounds clamp;

It looks like the docs are slightly out-of-sync.

[louisgag]

Using the openfoam 1.5 package, I had to manually set the $FOAM_CASE variable before running paraFoam to avoid an error that would cause it to exit before any rendering could be done. (That is in the case of a time varying inlet velocity).

[olesen]

I've reported this and it's already been fixed for the next release.
If you are willing to patch the source a bit, the changes to vtkPV3Foam.C are quite simple:

In the Foam::vtkPV3Foam::vtkPV3Foam constructor
you need these lines:

// avoid argList and get rootPath/caseName directly from the file
fileName fullCasePath(fileName(FileName).path());

if (!dir(fullCasePath))
{
return;
}
if (fullCasePath == ".")
{
fullCasePath = cwd();
}

// Set the case as an environment variable - some BCs might use this
if (fullCasePath.name().find("processor", 0) == 0)
{
setEnv("FOAM_CASE", fullCasePath.path(), true);
}
else
{
setEnv("FOAM_CASE", fullCasePath, true);
}

[louisgag]

Thank you Mark.

By adding

// Set the case as an environment variable - some BCs might use this
if (fullCasePath.name().find("processor", 0) == 0)
{
setEnv("FOAM_CASE", fullCasePath.path(), true);
}
else
{
setEnv("FOAM_CASE", fullCasePath, true);
}



after

fileName fullCasePath(fileName(FileName).path());

if (!dir(fullCasePath))
{
return;
}
if (fullCasePath == ".")
{
fullCasePath = cwd();
}



my problem was solved.

[woody]

Hello Guys,

Just for completion of this thread: I tried to restart my simulation with the new Version.
There seemed to be a change in the file Format of the TimeVaryingUniformFixedValue BC, at least for varying velocities. My old file looked like:
(
t1 U1
t2 U2
t3 U3
...
)

The new file has to look like:

(
(t1 (Ux1 Uy1 Uz1))
(t2 (Ux2 Uy2 Uz2))
(t1 (Ux3 Uy3 Uz3))
...
)

Obviously somebody managed to change the Velocitydescription from normal to cartesian...
would be nice if such things are posted somewhere....

Hope this helps anyone who starts with this BC