[Bloerb]

I am currently trying to better understand the energy equations used in OpenFoam solvers. http://cfd.direct/openfoam/energy-equation/ seems like a good start if you want to look at this yourself.

Now chtMultiRegionSimpleFoam or buoyantSimpleFoam for example use the following form:

    fvScalarMatrix EEqn
    (
        fvm::div(phi, he)
      + (
            he.name() == "e"
          ? fvc::div(phi, volScalarField("Ekp", 0.5*magSqr(U) + p/rho))
          : fvc::div(phi, volScalarField("K", 0.5*magSqr(U)))
        )
      - fvm::laplacian(turb.alphaEff(), he)
     ==
        rho*(U&g)
      + rad.Sh(thermo)
      + fvOptions(rho, he)
    );

This is a simplified version of the one in the link and lets us choose between e and h as the variable. I'd say this is how it reads:

Internal Energy:

Enthalpy:

Now the source terms are for radiation or heat generation in the domain for example. You can check fvOptions for what is possible.

Now my question: Why don't we use temperature directly? What are the drawbacks or advantages of using T, h or e? Can someone direct me to a good derivation of this equation? I want to understand the simplifications used and when they become critical. For example it seems that the dissipation of mechanical energy into heat is omitted.
Can someone direct me to a good source on how these equations come about?

[sharonyue]

I did not test the drawbacks of using T, this should be more clarified by some papers. Regarding T, OpenFOAM indeed solves T in certain solver, or in certain version. For example, in OpenFOAM-2.2.x, it solved TEqn for compressibleTwoPhaseEulerFoam, but it was replaced soon by E or HEqn in OpenFOAM-2.3.x. When you solve for T, there is an assumption that T is linear with E or H.
Check it here from the Official document:
http://cfd.direct/openfoam/energy-equation/
I have a full derivation of the energy equtions as well:
http://dyfluid.com/energy.html

Yes, the mechanical source is neglected.

[DustExplosion]

Does anyone have a reference for neglecting the mechanical energy? Just typesetting equations now for my thesis and realized it is not included!

[stomibo]

Hi Chris,

I'm also working for my thesis with chtMultiRegionSimpleFoam and realized that the mechanical term is missing, but I don't know why. Anyway, as descriped here:
https://cfd.direct/openfoam/energy-equation/
at the end of paragraph 4, I just copied the mechanical source from rhoCentralFoam. I'm not sure yet, if it's working properly, but the results seem to be realistic. At least they seem to be more realistic than without the mechanical term, respectively

Michael

[LuckyTran]

The viscous dissipation of mechanical energy into heat is often omitted by choice. Usually it is a small contributor and sometimes you want the convenience of a globally conserved energy transport equation.

People that want realistic simulations like to include the viscous dissipation term. People that want to understand their result better, leave it out. You cannot do like isentropic or isenthalpic flow in a duct for example if you include them.

[DustExplosion]

Thank you for the replies.

My simulations are 1D multiphase flames in air or methane gas. In both cases I would think the viscosity of air would be quite low and the mechanical losses due to viscosity would be low.

I will have to take a look - does anyone have any information on what is typically done for these types of simulations?

[LuckyTran]

Viscous dissipation is even easier to neglect in combustion because temperature gradients become very large and the viscous dissipation is an even smaller component of the overall heat flux.

Many combustion modelling approaches even assume explicitly that the flow is isenthalpic.

To even have viscous dissipation in the first place, you need shear layers (i.e. walls), and strong ones. For example, order of magnitude analysis on a Blasius flat plate shows that the viscous dissipation is negligible until the freestream velocity is 100 m/s or so. But this is for a problem with no heat transfer. As soon as you heat the plate, the conduction and convection heat transfer pretty much overwhelm the problem.

Btw you can post-process your result and calculate, for the given resulting velocity field, what the viscous dissipation ought to be. This will give you a 95% of the answer.

[DustExplosion]

Thanks for the information and the tip LuckyTran. I will plot out my velocity gradients and check the magnitude of this term, but it sounds like it will be insignificant (velocity gradients in the flame are relatively small going from 0~3 m/s through the flame thickness)

[DustExplosion]

Just an update on this. If anyone needs a reference "An Introduction to Computational Fluid Dynamics" second edition by Versteeg and Malalasekera states in Section 12.14 (pg 364) "Viscous energy dissipation is normally assumed negligible in low Mach number combusting flows".

[S03r3n]

Originally Posted by stomibo

Hi Chris,

I'm also working for my thesis with chtMultiRegionSimpleFoam and realized that the mechanical term is missing, but I don't know why. Anyway, as descriped here:
https://cfd.direct/openfoam/energy-equation/
at the end of paragraph 4, I just copied the mechanical source from rhoCentralFoam. I'm not sure yet, if it's working properly, but the results seem to be realistic. At least they seem to be more realistic than without the mechanical term, respectively

Michael

Can you send me your implementation?
Thanks in advance!