[smog]

Hello all,

I want to region-refine a patch (imported from a .stl file and included in the "regions" section of the Geometry subdict in sHMD [with the same name as the .stl patch]). Has anyone tried it yet?

As it goes, the geometry of my .stl file is such that I cannot use a refinementBox/refinementSphere/etc. for this volume refinement. It would be simpler for me to just refine the region bounded by this patch. Any ideas as to what the syntax should be? This documentation link says it is possible (at the bottom of the page).

http://www.openfoam.org/version2.2.0/snappyHexMesh.php

"users can now specify surface names for region refinement using wildcards; "



Any help will be highly appreciated.

P.S: I tried these permutations before and failed to refine the region:
1) stlFileName.stl_patchname
2) "patchame"
3) "patchname_*"

[seanmike31]

HI, I found this tutorial on youtube. Try it.

https://www.youtube.com/watch?v=ObsFQUiVi1U

[smog]

I have seen this tutorial. Unless I missed the part where he talks about this problem.

[danielpiaget]

Hello Smog,

In snappyHexMesh, one can define patch(es) or surfaces geometry in the following ways.

The first method is when the blockMesh mesh is defined. I recommend that you id all 6 surfaces with patches names.In other words, inside the blockMeshdict defines each patch with the 4 summit points (in counter-clockwise fashion).

The second method is inside the stl file. Each patch can be separated likes this:
---------------------------------------------------------------
solid outlet

facet normal +0.0000000E+00 +0.0000000E+00 +1.0000000E+00
outer loop
vertex -2.0000000E-01 +1.5000000E-01 +2.0000000E+00 vertex -2.0000000E-01 -1.5000000E-01 +2.0000000E+00 vertex +2.0000000E-01 -1.5000000E-01 +2.0000000E+00
endloop
endfacet
…
endsolid
-------------------------------------------------------------------

Once all that works fine, you can define inside the Geometry section
a region as follows:

regions
{
outlet
{
name my_outlet;
}

}


See also the links below:

https://sites.google.com/site/snappy...t#TOC-geometry
https://openfoamwiki.net/images/f/f0...SlidesOFW7.pdf

Daniel

[smog]

That is not an answer to my question. I can very well define a patch in the sHMD, my question was whether I can refine the volume bounded by a patch.

[wyldckat]

Greetings to all!

I was wondering about this today as well and diagnosed it with a modified case of the tutorial "heatTransfer/buoyantBoussinesqSimpleFoam/iglooWithFridges". I added a new STL file to the case named "sliced0.stl" and then added the following to "system/snappyHexMeshDict":

• Inside the "geometry" block:
  

      sliced0.stl
      {
          type triSurfaceMesh;
  
          regions
          {
              ascii
              {
                  name myPlane;
              }
          }
      }

• Inside the "castellatedMeshControls.refinementRegions" block:
  

          sliced0.stl
          {
             mode distance;
             levels ((0.3 4) (0.6 3));
          }

  Note: The name "myPlane" cannot be used inside this block.

In case you assigned a new name for the STL, for example:

    sliced0.stl
    {
        type triSurfaceMesh;
        name mySlice;

Then it's the name "mySlice" that has to be used in "castellatedMeshControls.refinementRegions".


Therefore, you cannot use the name for one of the solids inside the STL and you should be careful with whether you renamed the main STL geometry.

This is the feature that smog pointed out from the release notes for OpenFOAM 2.2.0 .

Best regards,
Bruno

[smog]

Thank you Bruno for the reply. Exactly what I needed, although I worked around the problem in the same way as you did- adding another .stl file and refining that region. Works perfectly fine.