|
[Sponsors] |
H-energy imbalance and P-mass imbalance does not converge. |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
February 20, 2023, 09:25 |
H-energy imbalance and P-mass imbalance does not converge.
|
#1 |
New Member
Anusai Ramankutty
Join Date: Dec 2019
Posts: 9
Rep Power: 7 |
I have a CHT analysis being done, where I have small gaps upto 55 microns in the fluid domain. I also have rotating domain at 140000rpm.
I get high Mach number notice if I keep the physical timescale to be higher than 1e-5, and if I keep it as 1e-6, the imbalances in h-energy and p-mass in the fluid does not converge . Can anyone suggest how I can fix this? |
|
February 20, 2023, 11:28 |
|
#2 |
Senior Member
Join Date: Jun 2009
Posts: 1,880
Rep Power: 33 |
I assume you are solving the problem using double precision, correct?
Also, what are the dimensions range in your case? m vs microns, or mm vs microns?
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. |
|
February 20, 2023, 13:00 |
|
#3 |
New Member
Anusai Ramankutty
Join Date: Dec 2019
Posts: 9
Rep Power: 7 |
The total length of the domain is 160mm. The working fluid i am using is R1234yf
|
|
February 20, 2023, 17:52 |
|
#4 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,871
Rep Power: 144 |
Have yo read the FAQ on this? https://www.cfd-online.com/Wiki/Ansy...gence_criteria
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. |
|
February 20, 2023, 23:01 |
|
#5 |
New Member
Anusai Ramankutty
Join Date: Dec 2019
Posts: 9
Rep Power: 7 |
||
February 21, 2023, 03:17 |
|
#6 |
Senior Member
Gert-Jan
Join Date: Oct 2012
Location: Europe
Posts: 1,928
Rep Power: 28 |
I would first run at lower speed and make sure global energy and mass balances are correct. Then speed up step by step.
Have you read this FAQ carefully: https://www.cfd-online.com/Wiki/Ansy...gence_criteria Point 2 tells you that (boldly said) flow is pressure driven (= fast) and energy is momentum driven (=relatively slow). Given your small time steps, the development of temperature and related equations, develop much slower through your domain than the flow itself. Therefore I consider it convenient to switch off momentun and turbulence for a few iterations and only solve energy equation with a large timestep. You can do this by defining Expert Parameters. Set: - solve fluids = false - solve turbulence = false. You can do this on the run (add expert parameter section in the top ribbon), you don't have to stop the calculation for this. When changing these parameter from true (default) to false, you can change the timescale to e.g. 1e-3, to let temperature develop in the existing (and now frozen) flow field fast. When you see that the energy imbalance have dropped significantly, you can go back to previous settings, again on the fly. Don't forget to reduce timestep! Otherwise it will crash soon. You can repeat this procedure a couple of times to get everything converged within reasonable time. However, your end solution should always be based on iterations where all equations are solved simultaneously, with the same timestep! Last edited by Gert-Jan; February 25, 2023 at 10:24. |
|
Tags |
cfx, cht, flow, physical timescale, turbulence |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Activating gas radiation leads to energy imbalance | seph | FLUENT | 1 | August 2, 2022 13:33 |
Mass imbalance problem in multiphase water and steam CFX case | Antech | CFX | 1 | October 26, 2020 05:03 |
Turbomachinery Mass imbalance | sheaker | CFX | 12 | September 5, 2019 09:09 |
Energy imbalance | seojaho | CFX | 6 | June 21, 2016 21:35 |
ATTENTION! Reliability problems in CFX 5.7 | Joseph | CFX | 14 | April 20, 2010 16:45 |