CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > CFX

Fluid-Fluid interface as thin material

Register Blogs Community New Posts Updated Threads Search

Like Tree1Likes
  • 1 Post By urosgrivc

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   January 31, 2017, 00:51
Default Fluid-Fluid interface as thin material
  #1
Member
 
Adil Syyed
Join Date: May 2012
Posts: 49
Rep Power: 14
adilsyyed is on a distinguished road
I am performing analysis on a double pipe heat exchanger with the hot fluid in the outer shell and cold fluid in the inner tube.

Now I can model a solid domain between the two fluid domains and specify the material, or I can simply define a fluid-fluid interface and specify the interface thickness along with material.

My question is, if I specify a fluid-solid interface after modeling the metal tube, do I still need to give this interface the thickness and material? I already defined a solid domain of 1 mm thickness between the two fluid domains.
adilsyyed is offline   Reply With Quote

Old   January 31, 2017, 04:08
Default
  #2
Senior Member
 
urosgrivc
Join Date: Dec 2015
Location: Slovenija
Posts: 365
Rep Power: 12
urosgrivc is on a distinguished road
You do not need to model the solid domain (tube).

1. First you create 2 domains (outer fluid, iner fluid) and under heat transfer you check either thermal or total energy.

2. create an Interface (pick the pairing surfaces) and under fluid models
check no slip wall this means that no fluid can flow through the interface than Heat transfer options ocure and you can select
conservative interface flux (this will be thermal energy) and under interface model you have an option to select
thin material than select the material and its thicknes.

that is it... You will not be able to see volume temperatures of the tube in cfx post, only
on both sides (wals of the tube) and in the fluid domains ofcourse.

______________
The other option is to do a CHT simulation If you would do that you would need a third solid domain but why complicate if it is not nesecary

And the ansver for the last question is, no, if you model the solid tube domain than you dont have any additional interface material,
unles the tubes have let say a lot of lime stone on them that could be the interface material
, but you do hawe two (fluid solid) interfaces,
adilsyyed likes this.
urosgrivc is offline   Reply With Quote

Old   February 1, 2017, 01:11
Default
  #3
Member
 
Adil Syyed
Join Date: May 2012
Posts: 49
Rep Power: 14
adilsyyed is on a distinguished road
Quote:
Originally Posted by urosgrivc View Post
You do not need to model the solid domain (tube).

1. First you create 2 domains (outer fluid, iner fluid) and under heat transfer you check either thermal or total energy.

2. create an Interface (pick the pairing surfaces) and under fluid models
check no slip wall this means that no fluid can flow through the interface than Heat transfer options ocure and you can select
conservative interface flux (this will be thermal energy) and under interface model you have an option to select
thin material than select the material and its thicknes.

that is it... You will not be able to see volume temperatures of the tube in cfx post, only
on both sides (wals of the tube) and in the fluid domains ofcourse.

______________
The other option is to do a CHT simulation If you would do that you would need a third solid domain but why complicate if it is not nesecary

And the ansver for the last question is, no, if you model the solid tube domain than you dont have any additional interface material,
unles the tubes have let say a lot of lime stone on them that could be the interface material
, but you do hawe two (fluid solid) interfaces,
Thanks for the guidance. I am clear about it now.

PS: I may use solid domain IF the geometry i.e diameter of the outer fluid shell effects other parts of the geometry. Then to preserve the geometry this approach might be used.
adilsyyed is offline   Reply With Quote

Old   February 1, 2017, 01:14
Default
  #4
Member
 
Adil Syyed
Join Date: May 2012
Posts: 49
Rep Power: 14
adilsyyed is on a distinguished road
The two fluids does not mix, only heat transfer across the interface occurs.

What if I use water as first fluid and steam as second. There is no physical interaction, no mass transfer occurs. But still it becomes a two phase flow and requires two phase flow modeling.

How can one get around that problem.

PS: I asked a similar question in another thread, hope that's not a problem.
adilsyyed is offline   Reply With Quote

Old   February 1, 2017, 01:38
Default
  #5
Member
 
Adil Syyed
Join Date: May 2012
Posts: 49
Rep Power: 14
adilsyyed is on a distinguished road
Quote:
Originally Posted by adilsyyed View Post
The two fluids does not mix, only heat transfer across the interface occurs.

What if I use water as first fluid and steam as second. There is no physical interaction, no mass transfer occurs. But still it becomes a two phase flow and requires two phase flow modeling.

How can one get around that problem.

PS: I asked a similar question in another thread, hope that's not a problem.
This question has already been answered in the other thread. Thanks
adilsyyed is offline   Reply With Quote

Old   February 9, 2019, 22:16
Default Mass Transfer across Fluid-Fluid Interface
  #6
Member
 
Soumitra Vadnerkar
Join Date: Aug 2018
Posts: 70
Rep Power: 8
soumitra2102 is on a distinguished road
What if I want both Mass and Heat Transfer to occur between two domains?
What should I select? Can you please elaborate what does Conservative Interface Flux mean?
soumitra2102 is offline   Reply With Quote

Old   February 10, 2019, 06:46
Default
  #7
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,872
Rep Power: 144
ghorrocks is just really niceghorrocks is just really niceghorrocks is just really niceghorrocks is just really nice
Conservative interface flux means exactly what it says - the flux of the variable over the interface is conserved. This might sound obvious but a simple interpolation at an interface is not always conservative - meaning material is created or destroyed by the numerical approach of the interface.

By mass transfer do you mean your flow passes through it, or do you mean a mass fraction passes through it, such as water diffusing into a solid?
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum.
ghorrocks is offline   Reply With Quote

Old   February 10, 2019, 12:47
Default
  #8
Member
 
Soumitra Vadnerkar
Join Date: Aug 2018
Posts: 70
Rep Power: 8
soumitra2102 is on a distinguished road
Thanks.
And by mass transfer I mean fluid flow passing through the interface without any loss.

In my case, I have two exactly same fluid domains but with different geometries and with common cross section at the interface. I want to simply connect the two domains and allow fluid flow (carrying mass and heat) in-between the two domains as if there is no interface boundary; which option should I use?
soumitra2102 is offline   Reply With Quote

Old   February 10, 2019, 17:57
Default
  #9
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,872
Rep Power: 144
ghorrocks is just really niceghorrocks is just really niceghorrocks is just really niceghorrocks is just really nice
If you set up a interface between two fluid domains the default condition is that it allows fluid flow and all scalar variables with it (heat, volume/mass fraction, other scalars) to pass through the interface. No special handling is required.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum.
ghorrocks is offline   Reply With Quote

Old   February 27, 2019, 12:14
Default
  #10
Member
 
Join Date: Feb 2019
Posts: 30
Rep Power: 7
IronLyon is on a distinguished road
Quote:
Originally Posted by soumitra2102 View Post
Thanks.
And by mass transfer I mean fluid flow passing through the interface without any loss.

In my case, I have two exactly same fluid domains but with different geometries and with common cross section at the interface. I want to simply connect the two domains and allow fluid flow (carrying mass and heat) in-between the two domains as if there is no interface boundary; which option should I use?
I'm doing somethig similar with your case, fluid fluid but one is melt (liquid) metal (hot) and the other is the gas (forced convection). The simulation is the cooling process for the metal, and in the physical conditions there is no others (means the interface is just the gas and the metal). I think, once you choose the conservative interface flux the heat transfer just depends on the temperature of each fluid and the materials (including the physical properties).
IronLyon is offline   Reply With Quote

Reply


Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Setting the height of the stream in the free channel kevinmccartin CFX 12 October 13, 2022 22:43
Difficulty in calculating angular velocity of Savonius turbine simulation alfaruk CFX 14 March 17, 2017 07:08
Problem in setting Boundary Condition Madhatter92 CFX 12 January 12, 2016 05:39
error message cuteapathy CFX 14 March 20, 2012 07:45
Terrible Mistake In Fluid Dynamics History Abhi Main CFD Forum 12 July 8, 2002 10:11


All times are GMT -4. The time now is 02:21.