|
[Sponsors] |
Is it possible to set constant heat transfer coefficient at a wall? |
![]() |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
![]() |
![]() |
#1 |
Senior Member
Jordi Pina
Join Date: Mar 2015
Posts: 157
Rep Power: 11 ![]() |
Hello,
I’m reading the pag. 34 of this PhD Tesis* And it says that “a constant heat transfer coefficient is used for the thermal boundary condition. The value of the coefficient was chosen so that simulated replications matched the experimental values using reverse engineering.” As far as I know, when simulating a flow using a multiphase model, it is NOT possible to set the heat transfer coefficient constant between the wall and the fluid, because it is calculated at each time step. I have contacted the author and he said me that he set the h value constant. I use ANSYS Fluent and I really think that this is not possible, is it possible in CFX? As far as I know, it is not! I will appreciate your help! *https://www.google.es/url?url=https://www.sintef.no/globalassets/project/mpc/tofteberg_phd_2009_web.pdf&rct=j&frm=1&q=&esrc=s&s a=U&ved=0ahUKEwjPo_3XkOjLAhXBDxoKHVx4CjwQFggXMAE&u sg=AFQjCNFL-I9UFbQp3U0s1mZRAHeYmkWy-w |
|
![]() |
![]() |
![]() |
![]() |
#2 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,816
Rep Power: 144 ![]() ![]() ![]() ![]() |
This is possible in CFX and Fluent. This is a basic boundary condition which is commonly used.
You appear to be confused with interface boundary conditions where the heat transfer at the interface is calculated from the flow conditions, so the user does not specify a heat transfer coefficient (htc) value. But for external walls all CFD solvers I know of offer the option to set a htc. |
|
![]() |
![]() |
![]() |
![]() |
#3 |
Senior Member
Jordi Pina
Join Date: Mar 2015
Posts: 157
Rep Power: 11 ![]() |
Dear gorrhocks,
what the paper says to set constant, is the h between wall and internal fluid, not between wall and external fluid. |
|
![]() |
![]() |
![]() |
![]() |
#4 | |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,816
Rep Power: 144 ![]() ![]() ![]() ![]() |
You can set a heat transfer coefficient on a wall boundary on a fluid or a solid domain. You cannot set a HTC on an interface, as mentioned in my previous post:
Quote:
|
||
![]() |
![]() |
![]() |
![]() |
#5 |
Senior Member
Jordi Pina
Join Date: Mar 2015
Posts: 157
Rep Power: 11 ![]() |
Hi,
thanks for the interest. We have the following geometry: ![]() And in the paper the author says to set the heat transfer coefficient of flow-wall to a constant. I don’t think it is even possible, because this internal h coefficient is calculated. I know that I could set an external h with the environment, but what the author says to have done, is to set the internal h to a given value (5000W/m^2/K in his case). |
|
![]() |
![]() |
![]() |
![]() |
#6 |
Senior Member
Join Date: Jun 2009
Posts: 1,850
Rep Power: 33 ![]() |
Please read the documentation section about
Chapter 4: Turbulence and Near-Wall Modeling | 4.2. Modeling Flow Near the Wall | 4.2.4.1. Heat Flux You can override the internal calculation of the Wall Heat Transfer Coefficient. If the properties are constant, you may get away with it. For variable properties, there may be consistency issue between the hydrodynamic and thermal boundary layers that must be satisfied. Good luck Hope the above helps, |
|
![]() |
![]() |
![]() |
![]() |
#7 |
Senior Member
Jordi Pina
Join Date: Mar 2015
Posts: 157
Rep Power: 11 ![]() |
Hello guys,
you put me in the good way and I've finally found how to do it with Fluent, I copy the documentation for the people of the future! After a lot of research, I've finally found how to set a constant heat transfer coefficient. I copy what I've found and used: 5. Wall Heat Flux The wall heat flux function ( DEFINE_HEAT_FLUX) can be used to modify the way that the solver computes the heat flux between a wall and the neighboring fluid cells. For example, you can customize the heat transfer coefficient or the law-of-the-wall for temperature. The UDF presented below uses an internal heat transfer coefficient to specify the wall heat flux. It is another example of a UDF that utilizes the ADJUST function to adjust a computed value, and it is executed as a compiled UDF. The diffusive heat flux coefficients ( cid) are specified in this UDF. The diffusive heat flux ( qid) will then be computed by FLUENT using the following equation: qid = cid[0] + cid[1]*C_T(c0,t0) - cid[2]*F_T(f,t) - cid[3]*pow(F_T(f,t),4) /************************************************** *********************/ /* UDF for specifying the diffusive heat flux between a wall and */ /* neighboring cells */ /************************************************** *********************/ #include "udf.h" static real h = 0.; /* heat transfer coefficient (W/m^2 C) */ DEFINE_ADJUST(htc_adjust, domain) { /* Define the heat transfer coefficient. */ h = 120; } DEFINE_HEAT_FLUX(heat_flux, f, t, c0, t0, cid, cir) { cid[0] = 0.; cid[1] = h; cid[2] = h; cid[3] = 0.; } |
|
![]() |
![]() |
![]() |
![]() |
#8 | |
New Member
Rashiga Walallawita
Join Date: Mar 2013
Posts: 13
Rep Power: 13 ![]() |
Hi,
Sorry for the noob question. How do I input UDF to an interface? Do I have to de-couple the interface to do so? TIA Cheers, Rashi Quote:
|
||
![]() |
![]() |
![]() |
![]() |
#9 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,816
Rep Power: 144 ![]() ![]() ![]() ![]() |
CFX does not use UDFs. They are a Fluent thing. If you are using Fluent then you should try the Fluent forum.
If you want to put a source term on a boundary interface that is easy, you can do that in the GUI. No user function is required (unless your function is too complex for CEL).
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. |
|
![]() |
![]() |
![]() |
|
|
![]() |
||||
Thread | Thread Starter | Forum | Replies | Last Post |
How to set heat transfer coefficient and wall temperature | jpina | FLUENT | 1 | March 21, 2016 08:47 |
Question about heat transfer coefficient setting for CFX | Anna Tian | CFX | 1 | June 16, 2013 06:28 |
Error finding variable "THERMX" | sunilpatil | CFX | 8 | April 26, 2013 07:00 |
Concentric tube heat exchanger (Air-Water) | Young | CFX | 5 | October 6, 2008 23:17 |
Multicomponent fluid | Andrea | CFX | 2 | October 11, 2004 05:12 |