|
[Sponsors] |
multiple runs for lift and drag at various AOA |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
January 7, 2013, 02:59 |
multiple runs for lift and drag at various AOA
|
#1 |
Member
Stuart
Join Date: Jun 2012
Posts: 59
Rep Power: 14 |
I am currently modelling a wing (to validate my technique) and want to find the performance characteristics for the wing at several angles of attack. Basically I want to be able to hit run once and for it to keep running until all the AOA's I specified have been simulated and the data exported i.e.
1. Run simulation 2. Converge 3. Export results (ie. User points such as cL,cD and cM to exel spread sheet (or similar)) 4. Change AOA and repeat process, writing each new set of data onto a new line of the same excel spreadsheet. 5. Repeat until reaching an AOA of 15 degrees. that way I will end up with discrete lift and drag for aoa's of 2,4,6,8,10 degrees etc I am under the impression that setting up my domain and changing the components of the fluid velocity is the way to go about it, but I havent been able to find any tutorials that step through the process. I assume there is a way, so if anyone could give me some advice or point me towards a useful tutorial that would be awesome. Thanks in advance. Last edited by ShowponyStuart; January 7, 2013 at 03:25. |
|
January 7, 2013, 17:15 |
|
#2 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,871
Rep Power: 144 |
Look at the parametric design and possibly the optimisation tutorials for ANSYS Workbench. So you will need the Workbench tutorials for this, not the CFX ones.
|
|
January 7, 2013, 21:44 |
|
#3 |
Senior Member
Chris DeGroot
Join Date: Nov 2011
Location: Canada
Posts: 414
Rep Power: 18 |
You could also probably write a script to do this. Just have CCL files prepared for each flow angle (assuming this is just a change in your boundary conditions) and call cfx5solve with the additional argument "-ccl whatever.ccl". As for writing to excel you could generate a csv file by reading the out file with your script. Not sure if this is easier or harder than using Workbench.
|
|
January 12, 2013, 23:46 |
|
#4 | ||
Member
Stuart
Join Date: Jun 2012
Posts: 59
Rep Power: 14 |
Quote:
Quote:
I figured out how to do it in workbench. I've given a brief summary below how I did it, im new on this forum so im not sure about the etiquette but is it good form to make a bit of a tutorial to help anyone else with similar problems? I dont mind doing it, shouldnt take too long, but there is no point doing it if it isn't going to help anyone. Anyway, what I did was (for anyone wondering) Import the wing into design modeler then create my domain around it in there. Then I performed a body operation (rotate) to allow the wing to rotate around an axis. Then I made this a parameter (check the box next to the angle you are inputting for the amount of rotation) and called it "aoa". I then followed normal procedure all the way to the solve phase. After the first solve had been performed, I went into Result. Then I went to the expressions tab and right clicked on my cD,cL and cM and made them all output parameters. Then your workbench should look like the photo I have attached . After clicking the parameters box it looks like the second pic attached. Then I just added my parameters (in this case -5,0,2.5,5,7.5,10 for my angle of attacks) and make sure you check the "Exported" tab so you get a new design point for each parameter, so it should look like the 3rd picture. then just hit "update all design points" and away you go. For anyone that finds this while looking for a way to do this themselves, If I get a chance and anyone would like a little document made up as a bit of a tutorial I will try to do that. Or just pm me if you would like some clarification. Last edited by ShowponyStuart; January 13, 2013 at 00:50. |
|||
January 13, 2013, 00:53 |
|
#5 |
Member
Stuart
Join Date: Jun 2012
Posts: 59
Rep Power: 14 |
I did whip a quick tutorial, im not sure how technically correct it is (there is probably better ways to do it) but it worked for me.
Sorry its pretty rough, if I get a chance I will try and tidy it up when I get some spare time but its nearly impossible to get any decent amount of information into a file 97.7KB .doc file. grr, stupid attachment limit. For the mean time, I hope this helps someone. Last edited by ShowponyStuart; January 13, 2013 at 02:05. |
|
January 13, 2013, 13:54 |
|
#6 |
Senior Member
Chris DeGroot
Join Date: Nov 2011
Location: Canada
Posts: 414
Rep Power: 18 |
Cool, I'm sure this will help people.
|
|
March 1, 2016, 15:16 |
It Works
|
#7 |
New Member
L Gamble
Join Date: Feb 2016
Posts: 3
Rep Power: 10 |
Helped me out! Thanks for that info. It works with Fluent as well with the same procedure in case anyone is curious.
|
|
April 10, 2016, 08:20 |
workbench parametric design
|
#8 |
Member
alex
Join Date: Feb 2016
Location: chennai
Posts: 48
Rep Power: 10 |
hi guys
i already meshed my model in ANSA. i have meshed file so how to proceed for this situation. |
|
April 29, 2020, 09:03 |
|
#9 | |
New Member
saiakameer
Join Date: Apr 2020
Posts: 1
Rep Power: 0 |
Quote:
|
||
Tags |
aoa, multiple, runs, script, wing |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Pressure drag, friction drag and total drag? | Cheng | CFX | 9 | January 26, 2024 14:46 |
Incorrect Drag and Drag Coefficient for flow over a cylinder | ozzythewise | Main CFD Forum | 8 | June 13, 2012 07:24 |
Calculation of Drag Coefficient, Help Please | teek22 | CFX | 1 | April 26, 2012 19:41 |
Force vectors for drag during sweeping motion | aamer | FLUENT | 0 | April 18, 2011 09:17 |
Inviscid Drag at subsonic, subcritical Mach # | Axel Rohde | Main CFD Forum | 1 | November 19, 2001 13:19 |