|
[Sponsors] |
Best Way to Mesh a Channel with Spheres Constituting The Bed |
![]() |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
![]() |
![]() |
#1 |
Member
Will Crawford-Jones
Join Date: Jan 2021
Posts: 43
Rep Power: 5 ![]() |
Hello,
I'm intending on modelling sediment transport. As such, I have a rectangular channel with 1000s of hexagonally-packed spheres constituting the bed- these will all be stationary for now. Any advice on what the best means of meshing such a set up would be? So far I have tried trimmed mesh. This works well for the bulk of the channel but near the bed it becomes 'messy' (see attached images). I don't mind too much how difficult it is to do, but just want to ensure I get solution convergence to ensure the simulations are less computationally expensive. As an example, would people advise Immersed Boundary Method (though I don't think this is possible with Star-CCM+)? Is it possible to set up a trimmed mesh for the bulk of the channel but a polyhedral mesher for the part where the spheres are? I don't want to do DEM simulations as I will only be modelling on mobile sphere, the rest of them are stationary. For the mobile sphere I intend on using DFBI, overset mesh. Any comments/ discussion are welcome Thanks Will |
|
![]() |
![]() |
![]() |
![]() |
#2 |
Member
Pietro
Join Date: Jun 2021
Location: London
Posts: 40
Rep Power: 5 ![]() |
Hi Will,
Do you really need so many spheres? You might need a better prism layer mesh surrounding your sediment spheres. I would at least impose 10 layers, with low prism layer stretching (1.1 or 1.2). Ideal would be to have the last prism layer cell half the size of the first cell outside the prism layer. I would probably set it up all with the polyhedral or the trimmed mesher. But it is possible to have a polyhedral mesh for the sphere and trimmed mesher for the rest as well. You just need to create two different regions, one for the low region close to the spheres and the other for the bulk. To do so you need to separate the two bodies when modelling your CAD geometry. After that you need to generate the parts, and click on "assign parts to region", "create one region for each part". Finally create two meshes, assign the bulk region to the trimmed mesher and the sphere region to the polyhedral. hope this helps Pietro |
|
![]() |
![]() |
![]() |
![]() |
#3 |
Member
Will Crawford-Jones
Join Date: Jan 2021
Posts: 43
Rep Power: 5 ![]() |
Hi Pietro,
Thanks for the suggestions. I'll respond to each part separately: Do you really need so many spheres? I may well reduce this number later on. You might need a better prism layer mesh surrounding your sediment spheres. I would at least impose 10 layers, with low prism layer stretching (1.1 or 1.2). Ideal would be to have the last prism layer cell half the size of the first cell outside the prism layer. Thanks for the suggestion. I may try something like this. I would probably set it up all with the polyhedral or the trimmed mesher. But it is possible to have a polyhedral mesh for the sphere and trimmed mesher for the rest as well. You just need to create two different regions, one for the low region close to the spheres and the other for the bulk. To do so you need to separate the two bodies when modelling your CAD geometry. How do I separate the bodies? Do you mean when I create the geometry (which I am using Star-CCM+ for) I create two separate bodies that can be separate regions but combined as one domain? I shall look into this anyway After that you need to generate the parts, and click on "assign parts to region", "create one region for each part". Finally create two meshes, assign the bulk region to the trimmed mesher and the sphere region to the polyhedral. Thanks for the help Will |
|
![]() |
![]() |
![]() |
![]() |
#4 |
Member
Pietro
Join Date: Jun 2021
Location: London
Posts: 40
Rep Power: 5 ![]() |
Yes you need to do it when creating the geometry. I use the split feature in SolidWorks usually so not sure how to do it in star but shouldn't be too hard.
I suggest you to generate your mesh on a simplified geometry (just 1 or 2 spheres), manage to get the right sizes for the boundary layer, and then apply them to the real thing. |
|
![]() |
![]() |
![]() |
Tags |
immersed boundary method, mesh 3d, open channel flow, sphere geometry, trimmed mesh |
|
|
![]() |
||||
Thread | Thread Starter | Forum | Replies | Last Post |
[ICEM] how to mesh a pack bed reactor with contact spheres using ICEM? | NIU | ANSYS Meshing & Geometry | 4 | November 16, 2021 05:24 |
[ICEM] Bad Quality Hybrid Mesh External Flow | tim13 | ANSYS Meshing & Geometry | 0 | March 8, 2020 02:22 |
[snappyHexMesh] No layers in a small gap | bobburnquist | OpenFOAM Meshing & Mesh Conversion | 6 | August 26, 2015 09:38 |
[snappyHexMesh] Layers:problem with curvature | giulio.topazio | OpenFOAM Meshing & Mesh Conversion | 10 | August 22, 2012 09:03 |
fluent add additional zones for the mesh file | SSL | FLUENT | 2 | January 26, 2008 11:55 |