|
[Sponsors] |
Velocity slip boundary condition won't be satisfied: I get non-zero normal velocity |
![]() |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
![]() |
![]() |
#1 |
Member
Hüseyin Can Önel
Join Date: Sep 2018
Location: Ankara, Turkey
Posts: 47
Rep Power: 7 ![]() |
Hi,
I'm imposing slip type boundary condition for U at the top of my solution domain. However, I get non-zero normal velocity component at this boundary: ![]() I am really puzzled because as far as I know, slip BC imposes zero vertical component at the boundary. The vertical cylindrical boundary seen here has time-varying inlet-outlet (flow angle rotates with time) velocity of 10 m/s. So the 18 m/s vertical component at the top boundary I'm getting is clearly abnormal and non-neglectable. Note: the bottom boundary also has slip BC and the same happens there. How is this possible? Did anyone experience something like this? solver: pimpleFoam turbulence: laminar top BC: U slip, p zero vertical boundaries: time-varying inlet-outlet (flow angle rotates with time) ddt scheme: 2nd order div schemes: 2nd order momentum predictor: on nOuterCorrectors 2; nCorrectors 2; nNonOrthogonalCorrectors 1; Regards, Huseyin |
|
![]() |
![]() |
![]() |
![]() |
#2 |
Senior Member
Uwe Pilz
Join Date: Feb 2017
Location: Leipzig, Germany
Posts: 744
Rep Power: 15 ![]() |
You should set a defined p only at one cell, the p reference. And not at the boundary. p may change here.
__________________
Uwe Pilz -- Die der Hauptbewegung überlagerte Schwankungsbewegung ist in ihren Einzelheiten so hoffnungslos kompliziert, daß ihre theoretische Berechnung aussichtslos erscheint. (Hermann Schlichting, 1950) |
|
![]() |
![]() |
![]() |
![]() |
#3 | |
Member
Hüseyin Can Önel
Join Date: Sep 2018
Location: Ankara, Turkey
Posts: 47
Rep Power: 7 ![]() |
Quote:
Thanks for the heads-up, indeed, it is something that can be easily overlooked! I've set the pRefPoint to the middle of the domain, however, it did not work. The problem was setting pressure to fixedValue 0 on the same boundary as the velocity slip condition. Changing pressure to slip fixed my problem (although I've always though that slip BC is reasonable only for vector fields). Zero gradient also seems to work. The weird thing is, OpenFOAM does not complain about not being able to satisfy the given boundary conditions. I guess this is due to the segregated nature of the pimple solver algorithm; pressure and velocity systems are solved separately? FYI: OpenFOAM version is 2.4.0 Hope this helps others. Regards! |
||
![]() |
![]() |
![]() |
|
|
![]() |
||||
Thread | Thread Starter | Forum | Replies | Last Post |
Wind turbine simulation | Saturn | CFX | 60 | July 17, 2024 05:45 |
Table bounds warnings at: END OF TIME STEP | CFXer | CFX | 4 | July 16, 2020 23:44 |
CFD analaysis of Pelton turbine | amodpanthee | CFX | 31 | April 19, 2018 18:02 |
Wrong flow in ratating domain problem | Sanyo | CFX | 17 | August 15, 2015 06:20 |
Radiation interface | hinca | CFX | 15 | January 26, 2014 17:11 |