|
[Sponsors] |
issues with multiphaseEulerFoam solver for binary simulation in fluidized beds |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
May 15, 2023, 22:46 |
issues with multiphaseEulerFoam solver for binary simulation in fluidized beds
|
#1 |
New Member
Esmaeel
Join Date: Jul 2012
Location: Melbourne
Posts: 5
Rep Power: 14 |
Hi everyone, I am trying to study the particle size effects for a binary mixture in a fluidized beds. So the system is particle-fluid but we have three phases: particle1,particle2, and air. The problem that I am facing with multiphaseEulerFoam solver is that the air volume fraction goes below 0.38 and it becomes as low as 0.24. So, each particle volume fraction are around 0.37 for same cells and that leads to the high volume fraction for particle phase. Here is the phaseProperties dictionary. Can anyone please help me understand what is wrong with my phaseProperties which results in high solid concentration? Thanks.
/*--------------------------------*- C++ -*----------------------------------*\ ========= | \\ / F ield | OpenFOAM: The Open Source CFD Toolbox \\ / O peration | Website: https://openfoam.org \\ / A nd | Version: 10 \\/ M anipulation | \*---------------------------------------------------------------------------*/ FoamFile { format ascii; class dictionary; location "constant"; object phaseProperties; } // * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * // type basicMultiphaseSystem; phases ( particles particles2 air ); //referencePhase particles; particles { type purePhaseModel; diameterModel constant; constantCoeffs { d 2e-4; } alphaMax 0.62; residualAlpha 1e-6; } particles2 { type purePhaseModel; diameterModel constant; constantCoeffs { d 2e-4; } alphaMax 0.62; residualAlpha 1e-6; } air { type purePhaseModel; diameterModel none; residualAlpha 0.; alphaMin 0.38; } blending { default { type continuous; phase air; } } surfaceTension {} interfaceCompression {} drag { particles_dispersedIn_air { type Ergun; residualRe 1e-3; } particles2_dispersedIn_air { type Ergun; residualRe 1e-3; } } virtualMass {} heatTransfer { particles_dispersedIn_air { type RanzMarshall; residualAlpha 1e-4; } particles2_dispersedIn_air { type RanzMarshall; residualAlpha 1e-4; } } phaseTransfer {} lift {} wallLubrication {} turbulentDispersion {} // ************************************************** *********************** // |
|
May 16, 2023, 03:20 |
|
#2 |
Member
Utkan Caliskan
Join Date: Aug 2014
Posts: 42
Rep Power: 12 |
kineticTheoryModel is important for particle dynamics in multiphaseEulerFoam so you need to check that. Furthermore, I don't think current solver can handle two different particle phases properly.
|
|
May 16, 2023, 03:38 |
|
#3 | |
New Member
Esmaeel
Join Date: Jul 2012
Location: Melbourne
Posts: 5
Rep Power: 14 |
Quote:
Thanks for the reply. The current case is from fluidized bed tutorial and it uses RAS kinetickTheory. I am beginning to accept that two particle systems cannot be modeled with this solver but I might be wrong! |
||
June 5, 2023, 15:28 |
|
#4 |
Member
Mattia de\' Michieli Vitturi
Join Date: Mar 2009
Posts: 51
Rep Power: 17 |
The kineticTheory implementation requires major changes to be able to model multiple solid dispersed phases. In the present state it should be used only with one solid phase.
|
|
June 7, 2023, 01:17 |
|
#5 |
New Member
Esmaeel
Join Date: Jul 2012
Location: Melbourne
Posts: 5
Rep Power: 14 |
Thanks. I was wondering if other software like ANSYS-CFX or MFIX can do such modeling of multi-particle systems with euler-euler approach?
|
|
June 7, 2023, 02:24 |
|
#6 |
Member
Mattia de\' Michieli Vitturi
Join Date: Mar 2009
Posts: 51
Rep Power: 17 |
Yes, they can both model multi-particle systems. If you want to do that with OpenFOAM, you have to modify the kinetic class in multiphaseEuler (the main change is the in the radial distribution functions), add a model for a multi-particle maximum packing, and add a solid-solid drag.
|
|
June 7, 2023, 02:41 |
|
#7 | |
New Member
Esmaeel
Join Date: Jul 2012
Location: Melbourne
Posts: 5
Rep Power: 14 |
Quote:
|
||
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Is pressure-based solver adequate for a transient simulation ? | y__tb | FLUENT | 1 | May 24, 2022 00:15 |
solver selection_dynamic mesh_leak simulation | nikhil108 | OpenFOAM Programming & Development | 1 | August 13, 2020 18:14 |
solver selection_dynamic mesh_leak simulation | nikhil108 | OpenFOAM Running, Solving & CFD | 5 | August 13, 2020 18:12 |
How can I use solution from one simulation as initial condition on a remote solver? | Dano62 | CFX | 0 | October 21, 2015 18:45 |
Working directory via command line | Luiz | CFX | 4 | March 6, 2011 21:02 |