 |
 |
 |
|
|
|
[Sponsors] | ||||
September 30, 2013, 21:52
|
Diverging solution in transonicMRFDyMFoam
|
#1 |
|
New Member
Trent
Join Date: May 2013
Posts: 2
Rep Power: 0  |
Hi,
I am attempting to replicate a 2D compressor profile test case using the transonicMRFDyMFoam solver from the Density Based Turbo package for OpenFoam-1.6-extend. I have run the case in sonicFoam and have a reasonable result, which I am attempting to replicate in transonicMRFDyMFoam. sonicFoam results: sonicFoam_p_converged.png sonicFoam_U_converged.png The pressure and velocity transonicMRFDyMFoam results diverge very quickly. transonicMRFDyMFoam_p.png transonicMRFDyMFoam_U.png In the attached case, I used the keyword "cyclic" for the periodic boundary conditions (to model an infinite array of blades) at the top and bottom (using createPatch to merge two patches into one periodic patch), however I have also used 'cyclicGgi' periodic boundary conditions to the same result. I have been stuck on this problem for a while now, any help would be greatly appreciated. I have attached the set up files, however the full polymesh files were too large to attach, so only the 'boundary' polyMesh file has been included. sc10_tranconicMRFDyMFoam.tar.gz Thanks heaps |
|
|
|
|
|
April 29, 2014, 02:46
|
Hi
|
#2 |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Hi Trent,
Have you been able to run transonicMRFDyMFoam case of your's successfully ? I need some help in this regard. Can you please help me ? |
|
|
|
|
|
|
May 9, 2014, 18:06
|
|
#3 |
|
New Member
Join Date: May 2011
Posts: 28
Rep Power: 15 |
hi sam
please list more detail about what you want to know. rencently i am doing rans simulation by using transonicMRFDyMFoam for compressor. |
|
|
|
|
|
|
May 13, 2014, 00:53
|
Floating point exception (core dumped) in transonicMRFDyMFoam
|
#4 | |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Quote:
I have set up the case for radial inflow turbine passage. I have used cyclic boundary condition for periodic surfaces and overlap GGI between the rotating and stationary parts. When I run the case I am getting following error. Code:
sml5kor@BMH301562:~/OpenFOAM/sml5kor-1.6-ext/run/Turbine_CASE_29.04.2014$ transonicMRFDyMFoam
/*---------------------------------------------------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM Extend Project: Open source CFD |
| \\ / O peration | Version: 1.6-ext |
| \\ / A nd | Web: www.extend-project.de |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
Build : 1.6-ext
Exec : transonicMRFDyMFoam
Date : Apr 30 2014
Time : 10:02:43
Host : BMH301562
PID : 28172
Case : /home/sml5kor/OpenFOAM/sml5kor-1.6-ext/run/Turbine_CASE_29.04.2014
nProcs : 1
SigFpe : Enabling floating point exception trapping (FOAM_SIGFPE).
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
Create time
Create dynamic mesh for time = 0
Selecting dynamicFvMesh staticFvMesh
Reading thermophysical properties
Selecting thermodynamics package hPsiThermo<pureMixture<constTransport<specieThermo<hConstThermo<perfectGas>>>>>
Allocating field rho
Reading field U
Reading/calculating face flux field phi
Creating MRF model
Creating turbulence model
Selecting turbulence model type RASModel
Selecting RAS turbulence model kOmegaSST
kOmegaSSTCoeffs
{
Prt 0.9;
alphaK1 0.85034;
alphaK2 1;
alphaOmega1 0.5;
alphaOmega2 0.85616;
gamma1 0.5532;
gamma2 0.4403;
beta1 0.075;
beta2 0.0828;
betaStar 0.09;
a1 0.31;
c1 10;
}
Create Riemann solver
Allocating field rhoU
Allocating field rhoE
Allocating physDeltaT list for RK and Dual-Time Stepping
Starting time loop
Time = 5e-05
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
rho L2 Residual: 5.22287757622644
rho LInf Residual: 6.44791071235071
DILUPBiCG: Solving for omega, Initial residual = 0.00130432164252392, Final residual = 2.96795116630587e-09, No Iterations 1
bounding omega, min: -8706879.03922889 max: 81910182030.3853 average: 143455780.414936
DILUPBiCG: Solving for k, Initial residual = 1, Final residual = 6.44126182533454e-11, No Iterations 2
bounding k, min: -0.10155708303169 max: 3128.93273261909 average: 5.22430823460557
ExecutionTime = 22.19 s
performance data:
Head (m) = 153590.297255837
TOmega (W) = 105.444029188369
Eff (%) = -9.05754907371286
Forces = (0.116067242676771 0.448441765109099 1.03710250567382)
Moments = (-0.0109810410962604 -0.0145957547140102 0.00728641017051233)
Fluid power output:
dEm (W) = -1164.15631127401
Head (m) = 153590.297255837
forces output:
forces(pressure, viscous)((0.0246120695715455 0.0593173620106552 0.064901448211144) (0.0914551731052256 0.389124403098444 0.972201057462674))
moment(pressure, viscous)((-0.00701764721585918 3.55306881895442e-05 0.000938169101871696) (-0.00396339388040122 -0.0146312854021998 0.00634824106864064))
Time = 0.0001
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
bounding rho, min: -3571.52349710333 max: 135.300557117857 average: 0.0624592646242397
bounding rhoE, min: -5840210714.15816 max: 285770183.417902 average: 16821.1460355255
bounding U max: 9163515.75862727
bounding h, min: -559187.987560337 max: 1329471.19462314 average: 570184.378251595
rho L2 Residual: 5.75472688663313
rho LInf Residual: 7.10596896265805
DILUPBiCG: Solving for omega, Initial residual = 0.000870710888200336, Final residual = 4.13051427693362e-09, No Iterations 1
bounding omega, min: -485017.969038368 max: 82333537116.776 average: 144331930.942993
DILUPBiCG: Solving for k, Initial residual = 0.740046810060922, Final residual = 7.44167813561397e-09, No Iterations 3
ExecutionTime = 32.92 s
performance data:
Head (m) = 79014.871433648
TOmega (W) = 113.872177860226
Eff (%) = 0.263868113135903
Forces = (0.132477788867598 0.487273650008056 1.06569241218417)
Moments = (-0.011384295242643 -0.0150292348287509 0.00786881344809862)
Fluid power output:
dEm (W) = 43154.9596906303
Head (m) = 79014.871433648
forces output:
forces(pressure, viscous)((0.0453001853033088 0.115529386787037 0.125766544339912) (0.0871776035642893 0.371744263221019 0.939925867844254))
moment(pressure, viscous)((-0.00758893570416305 -0.000882449356738547 0.00179562705778156) (-0.00379535953847992 -0.0141467854720123 0.00607318639031707))
Time = 0.00015
Floating point exception (core dumped)
Could you please help me in this regard. Regards, Sam |
||
|
|
|
||
|
May 14, 2014, 05:09
|
|
#5 |
|
New Member
Join Date: May 2011
Posts: 28
Rep Power: 15 |
Hi, Sam
1. I have a look at the attached files. For the inlet boundary, total pressure, total temperature and flow direction are usually specified. I find that you did not set the inlet flow direction, but zeroGradient in 0/U file is set in the inlet patch instead. I think you can try the typical boundary condition provided by Borm. 2. According to my experience, you can first turn off turbulence, set a higher outlet pressure (e.g. 190000Pa) and set the rotating speed to zero. If this calculation works, then you can gradually improve the rotating speed and lower the outlet pressure. 3. For the inter-row treatment, which kind of method did you use? (mixing plane or frozen rotor) Last edited by dowlee; May 14, 2014 at 05:12. Reason: wrong words |
|
|
|
|
|
|
May 15, 2014, 03:01
|
|
#6 | |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Quote:
1. Can you provide me the typical boundary condition provided by Borm. ? Means where I can find them. 3. frozen rotor. means MRF method as Borm used in transonicMRFDyMFoam solver . |
||
|
|
|
||
|
May 15, 2014, 05:45
|
|
#7 | |
|
New Member
Join Date: May 2011
Posts: 28
Rep Power: 15 |
Hi, you will download the folder named densityBasedSolver in http://sourceforge.net/projects/openfoam-extend/.
There are some tutorials provided by Brom in the directory "densityBasedSolver/run" Quote:
|
||
|
|
|
||
|
May 17, 2014, 06:14
|
|
#8 |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
I was able to run the case but after 1000 iterations I am getting wrong flow rate .
Code:
Time = 1000
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
bounding U max: 46939.3687296215
rho L2 Residual: 5.19492515331512
rho LInf Residual: 6.6959350398147
DILUPBiCG: Solving for omega, Initial residual = 3.95477114014134e-06, Final residual = 2.94743732008884e-11, No Iterations 1
DILUPBiCG: Solving for k, Initial residual = 0.000135496572893564, Final residual = 4.27530898304972e-09, No Iterations 1
bounding k, min: -0.00138428982961019 max: 258480.340654354 average: 1085.527034435
ExecutionTime = 7105.86 s
MassFlows: INLET = 2.69804743578668e-09
MassFlows: OUTLET = 0.123375043979185
Averages of p : INLET = 200000 OUTLET = 100203.673206441
Averages of rho : INLET = 0.700070745782449 OUTLET = 0.696048056366656
Averages of T : INLET = 992.999999999999 OUTLET = 500.385591367588
Averages of U : INLET = (-1.50903942957102e-06 0 0) OUTLET = (4.30635301362846 4.48022752259606 98.9735954313029)
end
Pressure and Temperature are fine . What could be the reason for this ? |
|
|
|
|
|
|
May 19, 2014, 02:28
|
BC and Constant files
|
#9 |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Hi,
Please find the attached BC and Initial values of the case which has run but wrong mass flow. Let me know your feed back upon this . Regards, Sam |
|
|
|
|
|
|
May 19, 2014, 05:25
|
"libsimpleFunctionObjects.so"
|
#10 |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Code:
functions
(
inletMassFlow
{
type patchMassFlow;
functionObjectLibs
(
"libsimpleFunctionObjects.so"
);
verbose true;
patches
(
inlet_0
);
factor -23;
}
Whats the meaning of "factor -23;". How to calculate this ? I feel this factor only making some problem for my simulation . |
|
|
|
|
|
|
May 19, 2014, 06:19
|
|
#11 | |
|
New Member
Join Date: May 2011
Posts: 28
Rep Power: 15 |
Quote:
|
||
|
|
|
||
|
May 19, 2014, 06:28
|
'outputControlMode' not found in inletMassFlow
|
#12 |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Code:
Starting time loop
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 108
'outputControlMode' not found in inletMassFlow
Assuming: timestep
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 116
'outputInterval' not found in inletMassFlow
Assuming: 1
phi: phi
Compressible: 1
Turbulent: 1
LES: 0
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 108
'outputControlMode' not found in outletMassFlow
Assuming: timestep
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 116
'outputInterval' not found in outletMassFlow
Assuming: 1
phi: phi
Compressible: 1
Turbulent: 1
LES: 0
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 108
'outputControlMode' not found in areaAverage
Assuming: timestep
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 116
'outputInterval' not found in areaAverage
Assuming: 1
Time = 1
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
rho L2 Residual: 6.44313258180784
rho LInf Residual: 7.65994499810326
DILUPBiCG: Solving for omega, Initial residual = 0.00244809190957999, Final residual = 2.65944354682262e-09, No Iterations 1
bounding omega, min: -24070579.7366927 max: 182073584542.249 average: 319780497.816931
DILUPBiCG: Solving for k, Initial residual = 1, Final residual = 5.11096081209236e-11, No Iterations 3
ExecutionTime = 20.82 s
MassFlows: INLET = 1.76248019141362
MassFlows: OUTLET = 0.0595373845935599
Averages of p : INLET = 200000 OUTLET = 100000.341228185
Averages of rho : INLET = 0.710387031990251 OUTLET = 0.695171381547665
Averages of T : INLET = 978.579590078318 OUTLET = 500.000892595263
Averages of U : INLET = (-1.50903942957102e-06 0 0) OUTLET = (4.99964468397136 4.99890645781862 99.9962223316277)
Time = 2
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
rho L2 Residual: 6.09112121652158
rho LInf Residual: 7.21831669034706
DILUPBiCG: Solving for omega, Initial residual = 0.000171867025540015, Final residual = 6.85362954444674e-10, No Iterations 1
bounding omega, min: -8373293.02948838 max: 182228019464.836 average: 321729239.314316
DILUPBiCG: Solving for k, Initial residual = 0.0497553547344649, Final residual = 1.76120797453748e-10, No Iterations 2
ExecutionTime = 28.15 s
MassFlows: INLET = 1.30938549343049e-09
MassFlows: OUTLET = 0.0595352322647667
Averages of p : INLET = 200000 OUTLET = 100000.68756607
Averages of rho : INLET = 0.700070745782449 OUTLET = 0.695172520026074
Averages of T : INLET = 992.999999999999 OUTLET = 500.001805227856
Averages of U : INLET = (-1.50903942957102e-06 0 0) OUTLET = (4.99910923914695 4.99772011195967 99.9895354653937)
Time = 3
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
rho L2 Residual: 6.04557557426488
rho LInf Residual: 7.1978292209289
DILUPBiCG: Solving for omega, Initial residual = 0.000170850205219554, Final residual = 5.30721748237609e-10, No Iterations 1
bounding omega, min: -766813.296739794 max: 182364930358.078 average: 323558740.303541
DILUPBiCG: Solving for k, Initial residual = 0.021230682776069, Final residual = 7.83053164320755e-11, No Iterations 2
ExecutionTime = 35.19 s
MassFlows: INLET = 1.29037051276754e-09
MassFlows: OUTLET = 0.059531348423872
Averages of p : INLET = 200000 OUTLET = 100001.033089627
Averages of rho : INLET = 0.700070745782449 OUTLET = 0.6951736690745
Averages of T : INLET = 992.999999999999 OUTLET = 500.002706121094
Averages of U : INLET = (-1.50903942957102e-06 0 0) OUTLET = (4.99857272900048 4.99659077737812 99.9830652506599)
|
|
|
|
|
|
|
May 19, 2014, 06:31
|
|
#13 | |
|
New Member
Join Date: May 2011
Posts: 28
Rep Power: 15 |
Quote:
|
||
|
|
|
||
|
May 19, 2014, 06:35
|
|
#14 |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Hi,
Really that's not a problem. You are replying and guiding me so i am very thankful to u. Thank you very much. Can you share your personnel mail ID if you don't mind ? |
|
|
|
|
|
|
May 19, 2014, 06:38
|
|
#15 | |
|
New Member
Join Date: May 2011
Posts: 28
Rep Power: 15 |
Quote:
|
||
|
|
|
||
|
May 19, 2014, 07:45
|
|
#16 | |
|
New Member
Join Date: May 2011
Posts: 28
Rep Power: 15 |
Quote:
|
||
|
|
|
||
|
May 19, 2014, 07:49
|
|
#17 | |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Quote:
 I will contact you through this mail ID. |
||
|
|
|
||
|
May 19, 2014, 10:57
|
mass flow Out of range
|
#18 |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Hi ,
I tried with inletOutlet BC at OUTLET patch and laminar case but the output of mass flow remains the same .. which is as shown below. Code:
sml5kor@BMH301562:~/OpenFOAM/sml5kor-1.6-ext/run/Turbine_CASE_17.05.2014$ transonicMRFDyMFoam
/*---------------------------------------------------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM Extend Project: Open source CFD |
| \\ / O peration | Version: 1.6-ext |
| \\ / A nd | Web: www.extend-project.de |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
Build : 1.6-ext
Exec : transonicMRFDyMFoam
Date : May 19 2014
Time : 19:24:29
Host : BMH301562
PID : 26940
Case : /home/sml5kor/OpenFOAM/sml5kor-1.6-ext/run/Turbine_CASE_17.05.2014
nProcs : 1
SigFpe : Enabling floating point exception trapping (FOAM_SIGFPE).
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
Create time
Create dynamic mesh for time = 0
Selecting dynamicFvMesh staticFvMesh
Reading thermophysical properties
Selecting thermodynamics package hPsiThermo<pureMixture<sutherlandTransport<specieThermo<hConstThermo<perfectGas>>>>>
Allocating field rho
Reading field U
Reading/calculating face flux field phi
Creating MRF model
Creating turbulence model
Selecting turbulence model type laminar
Create Riemann solver
Allocating field rhoU
Allocating field rhoE
Allocating physDeltaT list for RK and Dual-Time Stepping
Starting time loop
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 108
'outputControlMode' not found in inletMassFlow
Assuming: timestep
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 116
'outputInterval' not found in inletMassFlow
Assuming: 1
--> FOAM Warning :
From function SolverInfo::SolverInfo(const dictionary& dict,const objectRegistry &obr)
in file SolverInfo/SolverInfo.C at line 87
Neither LES nor RAS found. Assuming no turbulence
phi: phi
Compressible: 1
Turbulent: 0
LES: 0
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 108
'outputControlMode' not found in outletMassFlow
Assuming: timestep
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 116
'outputInterval' not found in outletMassFlow
Assuming: 1
--> FOAM Warning :
From function SolverInfo::SolverInfo(const dictionary& dict,const objectRegistry &obr)
in file SolverInfo/SolverInfo.C at line 87
Neither LES nor RAS found. Assuming no turbulence
phi: phi
Compressible: 1
Turbulent: 0
LES: 0
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 108
'outputControlMode' not found in areaAverage
Assuming: timestep
--> FOAM Warning :
From function simpleFunctionObject::simpleFunctionObject
in file simpleFunctionObject/simpleFunctionObject.C at line 116
'outputInterval' not found in areaAverage
Assuming: 1
Time = 1
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
rho L2 Residual: 6.40372710604553
rho LInf Residual: 7.49081222690984
ExecutionTime = 14.52 s
MassFlows: INLET = 1.76248019141362
MassFlows: OUTLET = 0
Averages of p : INLET = 200000 OUTLET = 100000
Averages of rho : INLET = 0.710387031990251 OUTLET = 0.695170250561966
Averages of T : INLET = 978.579590078318 OUTLET = 500.000000000001
Averages of U : INLET = (-1.50903942957102e-06 0 0) OUTLET = (9.31784332147014e-18 7.85744018292775e-18 1.7403312614265e-17)
Time = 2
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
rho L2 Residual: 5.83719515087281
rho LInf Residual: 7.11130368620766
ExecutionTime = 18.25 s
MassFlows: INLET = 1.30938549343049e-09
MassFlows: OUTLET = -2.58934377791194e-20
Averages of p : INLET = 200000 OUTLET = 100000
Averages of rho : INLET = 0.700070745782449 OUTLET = 0.695170250561966
Averages of T : INLET = 992.999999999999 OUTLET = 500.000000000001
Averages of U : INLET = (-1.50903942957102e-06 0 0) OUTLET = (1.17465609866511e-17 3.25777301233301e-18 3.34564026928883e-16)
Time = 3
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
rho L2 Residual: 5.71596933487263
rho LInf Residual: 7.0872781206772
ExecutionTime = 22.05 s
MassFlows: INLET = 1.29037051276754e-09
MassFlows: OUTLET = 2.40670548093986e-19
Averages of p : INLET = 200000 OUTLET = 100000
Averages of rho : INLET = 0.700070745782449 OUTLET = 0.695170250561966
Averages of T : INLET = 992.999999999999 OUTLET = 500.000000000001
Averages of U : INLET = (-1.50903942957102e-06 0 0) OUTLET = (7.42904399900281e-18 8.66558587599736e-18 1.96335447031351e-15)
|
|
|
|
|
|
|
May 21, 2014, 08:36
|
mass flow problem
|
#19 |
|
Senior Member
Join Date: Sep 2013
Location: Bangalore India
Posts: 134
Rep Power: 13 |
Hi,
Now the case is running but gives some error after some 100's of iterations. The error is as follows Code:
Time = 2000
diagonal: Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUx, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUy, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoUz, Initial residual = 0, Final residual = 0, No Iterations 0
diagonal: Solving for rhoE, Initial residual = 0, Final residual = 0, No Iterations 0
bounding rho, min: -1057.88 max: 3688.91 average: 0.756053
bounding rhoE, min: -1.08367e+09 max: 1.20384e+10 average: 385827
bounding U max: 9.60207e+07
bounding h, min: -3.98146e+07 max: 7.099e+07 average: 620124
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
From function specieThermo<thermo>::T(scalar f, scalar T0, scalar (specieThermo<thermo>::*F)(const scalar) const, scalar (specieThermo<thermo>::*dFdT)(const scalar) const) const
in file /home/sml5kor/OpenFOAM/OpenFOAM-1.6-ext/src/thermophysicalModels/specie/lnInclude/specieThermoI.H at line 73
Maximum number of iterations exceeded. Rescue by HJ
rho L2 Residual: 6.93647
rho LInf Residual: 9.05835
DILUPBiCG: Solving for omega, Initial residual = 3.88886e-06, Final residual = 7.15152e-09, No Iterations 1
bounding omega, min: -3.69309e+09 max: 1.75975e+11 average: 3.65849e+08
DILUPBiCG: Solving for k, Initial residual = 0.00153104, Final residual = 2.9086e-10, No Iterations 3
bounding k, min: -61245.7 max: 3.02127e+07 average: 22009.7
ExecutionTime = 7454.68 s
MassFlows: INLET = 0.123706
MassFlows: OUTLET = -0.0734246
Averages of p : INLET = 175946 OUTLET = 105000
Averages of rho : INLET = 0.636106 OUTLET = 0.847162
Averages of T : INLET = 961.373 OUTLET = 495.48
Averages of U : INLET = (-159.772 0 0) OUTLET = (27.5507 9.71856 -17.1995)
end
Inlet pressure 2 bar Inlet temperature 973 K What would be the problem ? Please help me . Regards, Sam |
|
|
|
|
|
|
May 22, 2014, 04:40
|
|
#20 | |
|
New Member
Join Date: May 2011
Posts: 28
Rep Power: 15 |
Quote:
|
||
|
|
|
||
 |
|
|
Similar Threads
|
||||
| Thread | Thread Starter | Forum | Replies | Last Post |
| under-relaxation factors -> level of residuals | Zigainer | FLUENT | 19 | July 21, 2017 17:53 |
| grid dependancy | gueynard a. | Main CFD Forum | 19 | June 27, 2014 22:22 |
| diverging solution in bubble rise | shash | FLUENT | 0 | August 11, 2012 17:39 |
| IcoFoam parallel woes | msrinath80 | OpenFOAM Running, Solving & CFD | 9 | July 22, 2007 03:58 |
| Wall functions | Abhijit Tilak | Main CFD Forum | 6 | February 5, 1999 02:16 |
1Likes
Linear Mode
