[luckycfd]

Hi all,
How can i edit linear solvers (PCG,PBICG,...) of openfoam, then compile them?
Regards.

[kmooney]

Its open source so you can really do whatever you please with the linear solvers.

You might be better of starting with simpler OpenFOAM programming before diving into the linear solvers, it sounds like you are really just getting started...

[luckycfd]

ok tanx for your attention, but please help me how can i do it?
i copy the linear solver, for example PBC directory, in my home then compile this by wmake, but there is not exist Make directory in the PCG directory for compiling!

[luckycfd]

hi all,
how an i compile linear solver of openfoam?
for example, i copy PCG directory in my home then compile this by wmake, but there is not exist Make directory in the PCG directory for compiling! please help me. (i want edit this linear solver.)

[wyldckat]

Greetings Hassan,

Please study the following pages, before continuing to try and modify a linear solver:

• http://openfoamwiki.net/index.php/Ho...ure_to_icoFoam
• http://www.openfoam.org/docs/user/co...p#x10-690003.2
• http://openfoamwiki.net/index.php/Ho...dary_condition

The last one is the one that gives the closest instructions to the changes you want to make, but these intermediate steps are very important, so that you can understand better how to build and change OpenFOAM source code!

Good luck! Best regards,
Bruno

[luckycfd]

Hi,

In order to create and use the new linear solver myPBiCG:

1. cp –r $FOAM_SRC/OpenFOAM/matrices/lduMatrix/solvers/PBiCG $FOAM_RUN/myPBiCG
2. Replace all occurences of PBiCG inside PBiCG.H/.C with myPBiCG and rename these files to myPBiCG.H/.C.
3. create the directory structure : myPBiCG/Make, and create files and options in it.

files:
myPBiCG.C
LIB = $(FOAM_USER_LIBBIN)/libmyPBiCG


options:
EXE_INC = -I$(OBJECTS_DIR)
LIB_LIBS = \
$(FOAM_LIBBIN)/libOSspecific.o \
-L$(FOAM_LIBBIN)/dummy -lPstream \
-lz

1. wmake libso
2. then switched into cavity test case, added libs(“libmyPBiCG.so”); to controlDict in the cavity/system directory and edited system/fvSolution to use myPBiCG instead of PBiCG.

But when I run the cavity by icoFoan, I recevie this error at the end of running the case:
“Segmentation fault”
Why? what is this error? how can i solve this error?

[luckycfd]

any body? please help me?

[luckycfd]

friends? please

[wyldckat]

Greetings Hassan,

People that usually can help here in the forum, only do it when they have some spare time. So, please be patient

I followed your steps and as far as I can figure out, the only problem could be that you added too many things to the file "Make/options".

Since I had the trouble to follow your steps and to create both the library and the test case, attached are both ready for testing. I used OpenFOAM 2.2.x, but should work fine on any 2.2.

edit: next time you post code, please use the "[CODE]" marker, as exemplified in the second link on my signature.

Best regards,
Bruno

[luckycfd]

Greetings Bruno,
thank you very much
Best regards,
Hassan.

[luckycfd]

Hi,

After compile the new preconditioner(myDILUPreconditioner) Successfully in the same way for adding the new linear solver library(myPBiCG).
I add to controlDict in the cavity/system directory:
libs("libmyDILUPreconditioner.so");
and edite system/fvSolution to use myDILU instead of DILU.
But I recevie this error:

--> FOAM FATAL IO ERROR:  
 Unknown asymmetric matrix preconditioner myDILUPreconditioner
 
 
 Valid asymmetric matrix preconditioners :
 
 
 4
 (
 DILU
 GAMG
 diagonal
 none
 )
 
 
  file:  
 
 
     From function lduMatrix::preconditioner::New(const solver&, const dictionary&)
     in file matrices/lduMatrix/lduMatrix/lduMatrixPreconditioner.C at line 123.
 
 
 FOAM exiting

please guide me how can I use my preconditioner?


Best regards,
Hassan.

[wyldckat]

Hi Hassan,

Go into the folder where you have the "myDILUPreconditioner" source code and run:

wclean all

Then compress the folder of the source code "myDILUPreconditioner" and attach the compressed file on your next post.

This way I'm able to tell you what you forgot to do.

Best regards,
Bruno

[luckycfd]

thank you,
source file is attached.

[wyldckat]

Hi Hassan,

It's simple. Notice these two lines in the header file "*.H"?

    //- Runtime type information
    TypeName("DILU");

You should change it to:

    //- Runtime type information
    TypeName("myDILU");

Best regards,
Bruno

[luckycfd]

Mr. Bruno
It,s OK!
Thank You very very much

best regards,
Hassan

[luckycfd]

Greetings Bruno,

Why the options file of myPBiCG can be empty? I use two diffrence form of options file, but both of them seems true! What is the difference between options_1 and options_2 files that is attached?

Best regards,
Hassan.

[wyldckat]

Hi Hassan,

There are two details you need to check:

1. After changing the "options" file, did you run the following command?
   

   wclean libso

2. When you run:
   

   wmake libso

   you have to look at the output and look for the lines that start with "SOURCE", then see what occurrences there are of "-I", which indicate which folders have headers files that should be added to the search list for the file being currently compiled.
   • The default option usually is to always include the "$(FOAM_SRC)/OpenFOAM/lnInclude" folder.
   • In this case, it's possible that myPBiCG doesn't need anything from the "finiteVolume" header files.

Best regards,
Bruno

[luckycfd]

Thank you Mr. Bruno,


Yes, I run

wmake libso

then

wmake libso

.
In the output, lines that start with "SOURCE", show occurrences that I added in the options file, but how can I find out which folders have headers files that should be added to the search list for the file being currently compiled?


Best regards,
Hassan

[wyldckat]

Well, whenever the compiler complains about not finding a header file, you can use the find command like this:

find $FOAM_SRC -name the_name_of_the_header_file.H

Usually you should include the entries for the "lnInclude" folders.

[luckycfd]

Thank you Mr. Bruno