[germangsilva]

hi Carlitos

I'm doing studies of fluidized bed (gas-solid), I'm using cfx11 or 12, and applying LES, but I have great difficulty setting the program cfx, I ask your help please. my email is germangsilva@gmail.com

[mvoss]

sorry,.. wrong thread.

[Josh]

This is a helpful thread, guys.

However, my problem is that I want to export the pressure and friction coefficients from a polyline of a transient simulation for averaging. Can this be done in Post? You can't create a polyline in Pre.

The only idea I've had so far (besides manually exporting each Cp/Cf graph at each timestep) is to use the Export Results option in Pre to export my pressure and wall shear surface data on the airfoil at each timestep. I'm not sure this would even produce the desired files.

Any help is much appreciated!

[mvoss]

hi,

you can either use a session-file-script or the transient graph option within CFX-Post.

neewbie

[Josh]

Thanks for the reply, neewbie (I feel weird calling you that since you obviously are more adept with CFX than I am).

I've avoided scripting as I have a terrible fear of programming, particularly PERL.

Doesn't the transient graph option only work for single values (e.g., maximum pressure versus time)? I need the entire Cp/Cf distribution on the airfoil at every timestep.

[Lance]

Hi,
use the PERL script in the beginning of this thread (CycLone, February 13, 2008, 16:00). - No need for you to do any PERL programming, just copy/paste
I use it often to export lines, polylines, or even surfaces from my transient simulations.

[mvoss]

hi also Senior Member (which i think feels weird ),

no need to fear PERL. Basicly your task is pretty easy.
1. open post
2. activate the session recording.
3.1. open the res. file
3.2. create the line, do the math and create one graph
3.3. export the graph via "export data to csv" (not sure about the nomenclature) and name it by smth. appropriate
4. stop recording
5. open the session file and include after the LOAD of the res.-file

!     $List = getValue("DATA READER","Timestep List"); #this looks for all trn.files
!    print "$List \n"; #shows the result of the search
!    @Wert = split(/,/,$List); #makes it accessible for further tasks
!    $lastFrame=$List[$#timestepList]; # very nice, this gives you the number of the last frame, nice for animations
!    foreach $List(@Wert){ #the MAINTASK, do the line and graph and export for every trn.file, see below
>         load timestep = $List #load the timestep
!         print "calculating for TIMESTEP $List \n";
!        ($time, $timeunits) = evaluate("Time");

now comes the session recording of the line, graph and export, so just adjust the name of the exportfile to $List

add an
[/CODE]
! }
[/CODE]
at the very end of the file.
Save the file in your working directory, start the CFX-CommandLine and execute the script by cfx5post - batch script.txt



neewbie

[Josh]

Hi guys -

Thanks for the helpful replies.

Neewbie -

The first file writes fine when I run the batch, but then I receive the following error:

-- ERROR -- CCL parser failed with message:
parseCCLLineH: syntax error near "[/CODE]"

It's just a simple syntax error, apparently, but I can't see anything wrong.

Here's my altered code:
____________________________________________

# Session file started: 2010/09/30 23:56:19
# CFX-12.1 build 2009.10.15-23.08

# To avoid unnecessary file pre-processing and modifications, include
# COMMAND FILE at the top of your session file.
# If it is not included, the file is assumed to be older and will be
# modified for backward compatibility.
COMMAND FILE:
CFX Post Version = 12.0
END

DATA READER:

Clear All Objects = false
Append Results = false
Edit Case Names = false
Open to Compare = false
Multi Configuration File Load Option = Last Case
Open in New View = true
Keep Camera Position = true
Load Particle Tracks = true
Files to Compare =
END

DATA READER:
Domains to Load=
END
> load filename=C:\Users\counsil\Documents\Thesis Simulations\First Paper\Re=5E4\\
AoA=5\SST\NACA0012_Re=5E4_AoA=5_SST_2D_files\dp0\C FX-1\CFX\Fluid Flow_016.res, \
force_reload=true

! $List = getValue("DATA READER","Timestep List"); #this looks for all trn.files
! print "$List \n"; #shows the result of the search
! @Wert = split(/,/,$List); #makes it accessible for further tasks
! $lastFrame=$List[$#timestepList]; # very nice, this gives you the number of the last frame, nice for animations
! foreach $List(@Wert){ #the MAINTASK, do the line and graph and export for every trn.file, see below
> load timestep = $List #load the timestep
! print "calculating for TIMESTEP $List \n";
! ($time, $timeunits) = evaluate("Time");

>readstate filename=C:\Users\counsil\Documents\Thesis Simulations\First Paper\Re=\
5E4\AoA=5\SST\NACA0012_Re=5E4_AoA=5_SST_2D_files\d p0\CFX-1\CFX\\
Polyline_Cp_Cf.cst, mode = overwrite, load = false, keepexpressions = true

EXPORT:
ANSYS Export Data = Element Heat Flux
ANSYS File Format = ANSYS
ANSYS Reference Temperature = 0.0 [K]
ANSYS Specify Reference Temperature = Off
ANSYS Supplemental HTC = 0.0 [W m^-2 K^-1]
BC Profile Type = Inlet Velocity
Export Connectivity = Off
Export Coord Frame = Global
Export File = C:\Users\counsil\Documents\Thesis Simulations\First Paper\Re=\
5E4\AoA=5\SST\NACA0012_Re=5E4_AoA=5_SST_2D_files\d p0\CFX-1\CFX\$List
Export Geometry = On
Export Node Numbers = Off
Export Null Data = On
Export Type = Generic
Export Units System = Current
Export Variable Type = Current
Include File Information = Off
Include Header = On
Location List = /POLYLINE:Polyline 1
Null Token = null
Overwrite = On
Precision = 8
Separator = ", "
Spatial Variables = X,Y,Z
Variable List = Cf, Cp, Length, xc
Vector Brackets = ()
Vector Display = Scalar
END
>export


# Session file stopped: 2010/09/30 23:58:12

[/CODE]
! }
[/CODE]

_____________________________________

It's probably a very simple mistake, but, like I mentioned, I'm a pretty useless programmer.

[Josh]

Well, like I said... I'm a useless programmer. After rereading my post, I realized I copied the "[/CODE]" part when I should have only copied the "! }"

Let that be a lesson not to debug late at night!

Thanks for everything, guys. Code works great.

[mvoss]

hi

... yes, the [CODE] snippet is from the online formular.
I suppose it´s running??
Check back for further questions.

neewbie

[Josh]

Well, the only questions I have are regarding expediting the process. If you feel like it...

Suppose I want to average all of the .csv files into one. I know I can write an external code with Python, e.g., to do this, but can it be done directly in the batch file?

[mvoss]

hi,

the thing is, that the batch doesn't know about the exported values. so, yes, you have to run another script for all of the csv files
OR
you create a lot of points, representing the "exported" line, link them to an expression like

! $CP=getExprVal("CP");
! $CP_POINT1=probe($CP, Point1);
store every "Point" in a separate list, average over the list.
But maybe you can do this way more easily in, ... let´s say EXCEL, if you have to do it only once.

neewbie

[Josh]

Thanks so much, MV. Cheers.

[hung]

Originally Posted by Lance

Hi,
use the PERL script in the beginning of this thread (CycLone, February 13, 2008, 16:00). - No need for you to do any PERL programming, just copy/paste
I use it often to export lines, polylines, or even surfaces from my transient simulations.

hi
Is anything changed with new version of CFX?
Couple of months ago I still run this command without any problems.
Now I got version 12.1 ANSYS and it seems something wrong here.
thanks

[mvoss]

hi,

which command? Afaik: there is a change in the nomenclature for variables e.g. the molar density.

neewbie

[hung]

Originally Posted by CycLone
;86065

Here's a crude session that will do the trick. Copy and paste it into your command window in Post and substitute your starting and finishing iteration numbers as well as your desire filename. Leave the "$i" in the name, as I have done below; Post will substitute the current value of the PERL variable $i into the name when it writes the file. You should first do a manual export to select the variables you want.

!$start = 0;
!$finish = 100;

!for($i=$start,$i<=$finish,$i++) {
> load timestep=$i

EXPORT:
Export File = export_$i.csv
END
>export
!}

-CycLone

This command.
I used to run this commands before.

[Lance]

Originally Posted by hung

This command.
I used to run this commands before.

note that the code should be:

!for($i=$start;$i<=$finish;$i++) {

that is, semicolon between the variables, not comma.
(at least for me...)

[hung]

Originally Posted by Lance

note that the code should be:

!for($i=$start;$i<=$finish;$i++) {

that is, semicolon between the variables, not comma.
(at least for me...)

thanks
it works

[Turbomachine]

Dear All!

I was trying to run the macro below as you suggested earlier in the topic:


COMMAND FILE:
CFX Post Version = 12.1
END
DATA READER:
Clear All Objects = false
Append Results = false
Edit Case Names = false
Open to Compare = false
Multi Configuration File Load Option = Last Case
Open in New View = true
Keep Camera Position = true
Load Particle Tracks = true
Files to Compare =
END
DATA READER:
Domains to Load = R1
END

! $PathSeparator = "/";
! $ResFileName = getValue("DATA READER", "Current Results File");
! $ResPos = index($ResFileName, ".res");
! $ResFileLength = length($ResFileName);

! if ($ResPos == ($ResFileLength - 4)){
! $FileBase = substr($ResFileName, 0, $ResFileLength-4);
! }
! else {
! $FileBase = $ResFileName ;
! }
! $DirName = $FileBase . "_EXPORT2";
! mkdir ($DirName, 0777);
! $DirName = $DirName . $PathSeparator;



! $count = 567;

! @tlistt = (567, 568, 569, 570, 571);

! foreach $tlist (@tlistt){

DATA READERATA READER
Current Timestep = $tlist
END
> load

! $dummyfile = $DirName . "t" . $count.".csv";

EXPORT:
#ANSYS Export Data = Element Pressure
#ANSYS Export Locator = wallmeshcdb
#ANSYS Fluid Selection = All Fluids
#ANSYS Reference Temperature = 0.0 [C]
#ANSYS Specify Reference Temperature = Off
Export Type = Generic
#BC Profile Type = Inlet Velocity
Export Connectivity = Off
Export Coord Frame = Global
Export File = $dummyfile
Export Geometry = Off
Export Node Numbers = Off
Export Null Data = Off
Export Units System = Current
#Export Variable Type = Hybrid
Include File Information = Off
Include Header = On
Location List = Blade1
Null Token = 0
Overwrite = On
Precision = 10
Separator = ", "
Spatial Variables = X,Y,Z
Variable List = Pressure, Total Mesh Displacement X, Total Mesh Displacement Y, Total Mesh Displacement Z, Normal X, Normal Y, Normal Z
Vector Brackets = ()
Vector Display = Scalar
END
>export

! $count = $count + 1;

! }



However I get an error below:


https://lh6.googleusercontent.com/_k...icture%202.png


Can anyone help me point out the problem?

Thank you very much

[pavitran]

Hi,

you can find the same post in page 2 also, however I am repeating the same thing again

copy the below macro in between hashes #, to some "file.cse" and copy file.cse to the directory where your *.trn files are located.

Being in the same directory, at the UNIX or Windows command line just type

cfx5post -batch file.cse ####for v11.0

cfx512post -batch file.cse ####for v12.0

cfx5121post -batch file.cse #### I guess for v12.1

As soon as you execute this and if everything is fine, I mean your location name , then on the screen you can see which case is presently in process.

eg:
:> cfx5post -batch file.cse
567
568
:>


Note : Before executing the above command, be sure to export DISPLAY, if using "putty" to connect to the LINUX machine.

export DISPLAY=IP:0.0 # IP address of windows machine

####################################
COMMAND FILE:
CFX Post Version = 12.1
END
DATA READER:
Clear All Objects = false
Append Results = false
Edit Case Names = false
Open to Compare = false
Multi Configuration File Load Option = Last Case
Open in New View = true
Keep Camera Position = true
Load Particle Tracks = true
Files to Compare =
END
DATA READER:
Domains to Load = R1
END

! for ($i=567; $i <= 571; $i=$i+1) {
! $file ="$i\_Full.trn" # eg: this loads 567_Full.trn file
! print "$file \n";
> load filename=$file, force_reload=true
EXPORT:
#ANSYS Export Data = Element Heat Flux
#ANSYS Reference Temperature = 0.0 [K]
#ANSYS Specify Reference Temperature = Off
# ANSYS Supplemental HTC = 0.0 [W m^-2 K^-1]
# BC Profile Type = Inlet Velocity
Export Connectivity = Off
Export Coord Frame = Global
Export File = $i.csv # Export file name with increment
Export Geometry = Off
Export Node Numbers = Off
Export Null Data = Off
Export Type = Generic
Export Units System = Current
Export Variable Type = Current
Include File Information = Off
Include Header = On
Location List = Blade1
Null Token = 0
Overwrite = On
Precision = 10
Separator = ","
Spatial Variables = X,Y,Z
Variable List = Pressure, Total Mesh Displacement X, Total Mesh Displacement Y, Total Mesh Displacement Z, Normal X, Normal Y, Normal Z
Vector Brackets = ()
Vector Display = Scalar
END
>export
!}
############################################