|
[Sponsors] |
Conjugated heat transfer (CHT): Solid not cooling down |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
August 5, 2017, 17:01 |
Conjugated heat transfer (CHT): Solid not cooling down
|
#1 |
Member
Join Date: Oct 2012
Posts: 32
Rep Power: 14 |
Hi all,
I have a problem understanding the conjugated heat transfer mechanism present at my model. The geometry consists of a block of copper (Dimensions: 10 mm (width) x 10 mm (height) x 100 mm (length) with a circular cutout (diameter 5 mm). Air at a temperature of 200 K and an inlet velocity of 1 m/s flows through the circular cutout of the copper block. The copper block has an initial temperature of 300 K and has a convective heat transfer of 10 W/mēK to the ambient temeprature of 300 K. Due to symmetry, I only modelled 1/4 of the problem. I set up my simulation model following the official ANSYS Tutorial Heat Transfer from a Heating Coil and the advice given in this video tutorial. After the simulation, I evaluated the average temperature of the with this expression: volumeAve(Temperature)@Solid The results look pretty much how I would expect them. I evaluated the temperature at both the solid and the fluid symmetry wall. You can see how the cold air stream gets heated up by the solid with increasing pipe length. The image below shows the results from a steady state simulation: steadystate.png I simulated 3 different cases and evaluated the average temperature of the solid accoroding to the formular stated above:
Many thanks in advance! |
|
August 6, 2017, 07:38 |
|
#2 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,871
Rep Power: 144 |
Before you go reading too mush into the results, have you done the basic checks that your simulation is accurate? If your simulation is inaccurate your results are rubbish so trying to read anything into the results is going to end in confusion. Read the FAQ: https://www.cfd-online.com/Wiki/Ansy..._inaccurate.3F
So: 1) Check your convergence is OK. I bet this is where the problem with your steady state simulation is ..... For CHT simulations you should include imbalances as part of your convergence criteria as only the imbalances checks that you have global conservation - and conservation of heat usually takes a lot longer than conservation of momentum in CHT simulations. So do another simulation with the residual tolerance 10x tighter and the imbalances 10x tighter. If it is the same as your previous simulation then you are OK. If not you have to tighten the tolerance by another 10x and keep going until you obtain convergence. 2) Check your mesh resolution. Repeat the simulation with half the mesh element edge length. Keep refining until you converge. 3) Check your time step size for the transient simulation. Halve the time step size and keep refining until you obtain convergence. Only after you have shown your simulation is accurate can you start thinking about what the results mean. |
|
August 6, 2017, 14:29 |
|
#3 |
Member
Join Date: Oct 2012
Posts: 32
Rep Power: 14 |
Dear Glenn,
thanks a lot for the advice with the imbalance, that saved my day . I had to run the steady state simulation much longer to obtain convergence of the thermal energy. The (converged) temperature of the Solid is now 269.5 K, which is in accordance to the transient simulation. Once again, thank you very much for helping me! |
|
August 6, 2017, 19:54 |
|
#4 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,871
Rep Power: 144 |
OK, you found a big error. But don't forget the rest of the comments in case there is a smaller error - make sure the other key sources of error are under control.
|
|
Tags |
cht, cht problem, conjugated heat transfer |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Heat transfer between solid rotating and stationary fluid domains | DCSERE | CFX | 2 | November 17, 2015 04:43 |
Error finding variable "THERMX" | sunilpatil | CFX | 8 | April 26, 2013 08:00 |
Enforce bounds error with heat loss boundary condition at solid walls | Chander | CFX | 2 | May 1, 2012 21:11 |
Modelling the heat transfer during compression and cooling of natural gas | pano | Main CFD Forum | 0 | December 10, 2010 16:53 |
conjugated heat transfer cooling flow over fuel rods | galapago | FLUENT | 0 | July 17, 2010 04:03 |