[Mmm2010]

Hello. Check up my project tutorial Submarine. Thank you.

[diamondx]

.tin file is missing in your project. can't load it.

[Mmm2010]

Sorry, 2g-2.zip this .tin file. (ICEM CFD 12.0.1)

[Far]

Originally Posted by PSYMN

You didn't send me the Tetin file (*.tin), so I didn't know where you set what sizes or prisms. I just set the global max to 2 and set a min size (sizing function) to 0.5. Then I hit compute mesh...

I am really confused about max size and min size. Why min size is size function and where I can set other attributes of size function and how does min size interact with max size?

Is there any effect of scale factor on min size?

[PSYMN]

During the Octree process, there is an initial subdivision where the volume is divided up into blocks. The size of these initial blocks is the max size multiplied by the scale factor...

So if your max size is 8 and your scale factor is 2.5, the blocks will all be size 20.

Then Octree starts to look at further refinement based on the entities within each block... It basically checks each and says "is there any settings within this block that are smaller than the current size". Lets say you had something size 3 in the block... It would check size 3*2.5=7.5 < 20, therefore subdivide. The single size 20 block is split on each side and becomes 8 (hence "octree") size 10 blocks. Then each of these is compared with the 7.5. Yup, 7.5 is less than 10, so they are subdivided again. Now you have a bunch of size 5 blocks, notice we ended up smaller than 7.5. This is why we suggest you stick with powers of 2 times a base size. Anyway, It checks each size 5 block again and concludes that they are less than 7.5, so the octree portion can stop on those blocks. Each block is then subdivided into 12 tetras, transitions are taken care of, smoothing, etc.

If you have curvature and proximity based refinement, then it will also check those. For instance, lets say you had set 3 cells in gap and 12 cells per 360 degrees, those become the "goals" of the refinement. It would want to keep refining until it met these requirements also. In some models, you may have a tiny gap or small curve you were not expecting. Lets say you had mostly gaps of 10 (leading to size 2.5 mesh in the above example because size 5 would not satisfy the requirement). Now imagine that somewhere in the model, you had a tiny gap, maybe 0.5. The octree subdivision would need 4 more steps to get down to that, 2.5 => 1.25 => 0.625 => 0.3125 (still too big for 3 across) => 0.15625! Each time it refines, the mesh count goes up by 2^3! at least in the local area, things could quickly get out of hand.

We need a way to limit that refinement; Min Size.

If we set the min size to something like 1, it is multiplied by the scale factor and becomes 2.5. This would be fine enough to allow it to reach the goal of 3 cells in gap for most of the model, but would not let it get rediculous in the little area I am not actually interested in...


So do you get it? Thes are Octree settings. Max size is the largest size you will see. Min size is a limit on refinement. All of them are multiplied by the scale factor.

Personally, I almost always leave my scale factor as 1 and always use powers of 2 for my sizes (1, 2, 4, 8, 16, 32, 64, etc.) I only adjust my scale factor if I want to tweak my mesh. For instance, if I wanted it 10% coarser, I would set it to 1.1.

[PSYMN]

Oh yea, I nearly forgot...

You can also set a max size and min size on parts. Previously, I was talking about the global Max and Min.

If you set them on parts, they work similarly.

Max on a part or surface or curve will cause the octree process to subdivide until it is less than or equal to that max size locally.

Min size on a part or surface or curve will cause the octree to go BELOW the global min size and allow you to refine further than normal near that entity. This can be handy if there is some tiny feature you want to capture, but you don't want unnecessary refinement happening all over...

[mhdasar]

I am new to ICEM CFD, i am getting problem please help me.

when i create a surface on a geometry which i want to mesh, it is overlapping on the body.
means when i hide Part_Face i can see the surface i created but when i start creating part i cant able to select that surface untill i hide face and if i hide and select the surface, that body is remain as it is.
how to solve this problem